[Chalkboard247]

I have a 5-axis Mori Seiki vertical. I'm familiar with how to loop a block of code, but I'm now trying to loop a block of code 5 times while changing the work offset from G54, G55, G56, so on. I'm wanting to do this so that when I alter code at the mill, I don't have to change a ton of copied code OR macro code OR subprogram code. I've searched everywhere and can't seem to find an answer. Does anyone have an idea on how this could be done? Thanks in advance!

[shags72]

Would something like this work?



Startup code to your preference
G0 G94 G17 G40 ......
g54
M98 p2222 (call to sub program, the O number)
G55
M98 p2222 (call to sub program, the O number)
G56
M98 p2222 (call to sub program, the O number)
G57
M98 p2222 (call to sub program, the O number)
G58
M98 p2222 (call to sub program, the O number)
M02

O2222

program code

M99 (return to calling program)

[norbert.barnard]

Hi,
main prog:
#100=54
M98 P2000 L5
..
.

O2000(SUB)
G#100
#100=#100+1(FOR NEXT REPEAT G5?)
.
.
M99

[sTruGGlebUs]

Both of these will work...but if you are trying to loop the block of code as a do while loop instead of calling a subprogram or macro:

#1=54.
WHILE[#1LE58.]DO1
G#1
whatever machining code you want to do
#1=#1+1.
END1