[bauhar]

Hello,
When I start following program it stops at line 114 and 021 PS alarm blink. What should be a reason for that? I try to change G 17 with G18 and G19, but results was the same.

%
O0000
(PROGRAM NAME - TEST2)
(DATE=DD-MM-YY - 26-08-06 TIME=HH:MM - 10:28)
N100G21
N102G0G17G40G49G80G90
(UNDEFINED TOOL - 1 DIA. OFF. - 1 LEN. - 1 DIA. - 20.)
N104T3
N106G0G90G54X40.Y0.S1909M3
N108G43H53Z50.
N110Z10.
N112G1Z0.F1500.
N114G3X-40.Z-6.586I-40.J0.
N116X40.Z-13.172I40.J0.
N118X-40.Z-19.757I-40.J0.
N120...
N138M5
N140Z100.
N144M30
%

Best regards,
bauhar

[Al_The_Man]

Did you try N100 G18?
Al.

[bauhar]

I replace G17 with G18 and G19 in N102, but without results. I think there is problem becouse all three axes go at the same time. If I go to -Z move first, the circle is OK, otherwise it stops. If I brake the circle on parts, there is no problem to go 3D, but the memory is to small for long programs. I tried to work with DNC, but par. 127 does not exist.(it is only one dig nr., not bit nr.)
bauhar

[Arrow Control]

Dont have a book with me to see what alarm stands for , but since its a 3 axis circular move on line 114 , I'd say yuour control doesn't have the Helical option turned on.

[Al_The_Man]

021 is Illegal Plane axis using either G17,G18,or G19.
To see if you have the options.
Check 907 bit 2 for Simultaneous 3 axis move.
Or 910 bit 3 for Helical Interpolation.
Al.

[Julian M]

you need to change the j for a k. Where k is the distance from the start point
to the centre of the arc(incremental), or the centre of the arc from z0(absolute)

[bauhar]

Al thanks, par. 910 was enabled. Now interpolation works.