[RPMW]

I am trying to engrave sequential serial numbers along with part number. The part number is easy but not having any luck with the sequential numbers does anyone have any help it would be much appreciated. I have not found any code to use, i have one i use on fadal machines but it doesn't work on this machine.

Thanks,
Richie

[pearrx123]

Can you tell me the version of software on the 840D control?

[RPMW]

version 05.0 flashes on screen when you start machine, is that what you are looking for. The machine is just now 1 year old

[kbarnett]

This is what we use on one of the parts we machine in our shop. We are engraving the purchase order then a sequential serial number at the end of the PO number. The information on how to set the first number to be used as the serial number is explained at the start of the process. We engrave the same information in two spots on the part because it has to be taken apart to assemble the internals. I hope this might help a little.

Kelly

N020 ;ENGRAVING PO AND SEQUENCE NUMBERS
N030 ;Establish start point here before canned cycle starts

N040 G0 X-1158 Y33 S3000 M3 M8

N050 ;Sequence the part from 1-999 then restart again
N060 ;The sequence value is located in ANZPROT parameter
N070 M00;MAKE SURE ANZPROT VALUE IS SET FOR FIRST SEQUENCE VALUE
N080 ;The sequence value is located in ANZPROT parameter
N090 ;TO LOCATE GO TO-USER DATA-PARAMETER-UGUD-ANZPROT"enter

N100 IF ((ANZPROT>=0) AND (ANZPROT<10))
N110 SINDIG:
N120 PROTNAME="2619801605-10-00"<<ANZPROT
N130 STOPRE
N140 GOTOF ENGRA
N150 ENDIF
N160 IF ((ANZPROT>=10) AND (ANZPROT<100))
N170 TENDIG:
N180 PROTNAME="2619801605-10-0"<<ANZPROT
N190 STOPRE
N200 GOTOF ENGRA
N210 ENDIF
N220 IF ((ANZPROT>=100) AND (ANZPROT<1000))
N230 HUNDIG:
N240 PROTNAME="2619801605-10-"<<ANZPROT
N250 STOPRE
N260 GOTOF ENGRA
N270 ENDIF
N280 FAIL:
N290 MSG(" ! NUMBERING EXEEDED ! ")
N300 M0
N310 GOTOB FAIL
N320 STOPRE
N330 ENGRA:

N340 G0 X-1158 Y33
N350 CYCLE60(PROTNAME,20,-1,3,-0.5,,-1158,33,0,,,20,8,250,400,0,1252,3)

N360 G0 X-1158 Y-42
N370 CYCLE60(PROTNAME,20,-1,3,-0.5,,-1158,-42,0,,,20,8,250,400,0,1252,3)
N380 ;=================
N390 ENDE:
N400 STOPRE
N410 ANZPROT=ANZPROT+1
N420 ;=================
N430 G80M5M9
N440 ZP=0
N450 TRANS
N460 G75Z1=0;Return Z axis to machine zero position

[RPMW]

thank you i will give that a try. I will let you know how it works.

[RPMW]

it did not work i get a 12550 alarm not defined or option/function not activated. It does not recognize the ANZPROT. I moved the cycle 60 to the user cycles restarted. Any suggestions.

Thanks,
Richie

[RPMW]

Softwarestand und Datum: ;VERSION: 07.05.11.00

[kbarnett]

There is something in the "data selection" background screens that is not activated for the engraving. The ANZPROT variable is also most likely not opened up to utilize. The best thing I can suggest is talk to the outfit that installed the machine to see if they have some "support" time left from the purchase of the mill. They will be able to get you where you need to be a lot faster than I can.

[pearrx123]

When you moved the cycle60 did you make sure it was loaded before you did the restart? And by restart you did mean power off and then power on?

[pearrx123]

You might also try the Siemens technical hotline at 1 800 879 8079. Phone support should be given at no charge.

[RPMW]

i did try the service line got the run around with no direct answer or fix. Was told to get with a tech that was out at one point in time and worked on the machine.

[jcruthers]

Do you have a technical support case number for when you called the service line?

[RPMW]

yes 1-316-296-7801

[jcruthers]

I work for the Siemens CNC business and pulled the case from our hotline. I have your contact information and will give you a call.


Sent from my iPad using Tapatalk - now Free

[CNC-Hammer]

I have seen two machines with canned cycle engraving function. The machinist cannot get the function to work although it appears to work in the simulation. Any ideas as to why this may be?

[kbarnett]

The machinist cannot get the function to work although it appears to work in the simulation. Any ideas as to why this may be?

Honestly, without better information on what messages are being given in the form of alarms or errors it could be a multitude of reasons for not working. I hate to put it like that, but there should be come errors or codes given when trying it at the machine I would think.

[CNC-Hammer]

Well that's exactly it. There is no alarm or error codes. It just does not work. All it does is engrave what is typed into the engraving cycle, no sequential count, nothing. I'm off the tools now and only see these guys occasionally so I'm just throwing it out there.
The m/c tool supplier tech has been out and can see nothing wrong, he just refers to the instruction manuals which are no help.

[kbarnett]

By chance could you post what the information is in the cycle 60 process you are trying to run? Maybe someone can se what area to target to get it to work. Thanks

[jcruthers]

The engraving cycle60 does not increment serial numbers automatically. It will engrave just what it's programmed to engrave. A solution found on the SINUMERIK forum on the Siemens Service & Support portal here: https://www.automation.siemens.com/W...rnet=False#top

It suggests using the a incrementing R variable and inserting the program text below in to the part program. Everything after the ; is a comment and is ignored

DEF STRING[10] _MTEXT ; create String


R1= R1 +1 ; count Part or whatever
_MTEXT =MMM << R1 ;Number convert to String
;_MTEXT is now "MMM1"
CYCLE60(_MTEXT,10,0,1,-0.05,0,10,.... ;Call Cycle

[RPMW]

;NCG#Gravur#\CST.DIR\gravur.com#NC1#2#*NCG;*RO*;*H D*
;#25#####4#1#3#6#7#7#2###3##4#2#2################# ################################################## ################################################## ###############################0###10#1##0#4#0#0#0 #0#0#0#0#0#1#0##1#0#1#12#0#S1#######1#0#0#1#10#1#1 #64#*NCG;*RO*;*HD*
CYCLE60("FAM STAGE 5 16-013AL 4-14",0.1,0,0.1,-0.495,,-3.2034,-7.8781,90,,,0.2,0.05,10,30,0,1252,3);*RO*
;#END#*NCG;*RO*;*HD*

this is the code from control when programmed in conversational at the machine, how can I add a sequential serial number to this.

Thanks,
Richie