[The Wolf!]

on my second day trying to get a damn hole drilled on the od of a part. ive gone round and round with the machine, dont even know were the hell im at, and what ive tryed. ive tryed working with the application engineer at haas, with no luck.

i do not have y axis. i have a endmill loaded in a live tooling holder. ive tryed the sample out of the book and alarms out.
could i get some sample programs from you guys see what is different then mine.

i have a st-30 haas lathe, no y axis, L11.07B software(i know out of date)
yes drilling on a mill is faster, but it is booked until xmas of 2250,lol

any and all help would be great.

thanks

[WallyL7]

May be better to post your program and we can try to see what is going on.

Also list what alarms you are getting...

[Markgyver]

%
O02430 ( G243 - RADIAL PECK
DRILLING )
G00 G58
G00 G53 Y0.
G00 G53 X0.
G00 G53 Z-7.
T505
M154
M133 P500
G98
G00 G53 X-2.
G00 C0.
G01 X6. Z0. Y0. C0. F30.
G00
G243 R5. X3. F30. I0.5 J0.2 K0.2
Y-2.
Y0. Z-1. C180.
G00 G80
G00 C0.
G00 G53 X0. Y0.
M135
M30

[Markgyver]

Here is a simplified G281 (same as a mill G81, but for radial drilling on Haas lathe).

%
O02410( G241 - RADIAL DRILLING)
G54
G00 G53 X0 Z-7.
T303
M19 P0
M133 P500
G98
G00 X6. Z-0.75
G241 R4. X2. F20.
Z-1.2
G00 G80 Z1.
G00 G53 X0.
M135
M30
%

[The Wolf!]

test #1
%
O00001
N5 T505 (RADIAL LIVE TOOL .1875 ENDMILL)
G19
G98
M154
G00 G54 X3. C0 Y0. Z1.
G00 X1.55 Z.25
G00 Z-2.06
G97 M133 P2500
/M8
G00 C0.
M14
G19 G243 X0 I.025 F6.
G00 X3.
Z-.365
G00 C180.
M14
G19 G243 X.5 I.025 F6.
G00 X3.
Z.1 M9
G18
G00 X8. Z8.
M30
%
alarm # 334 y axis disabled

test #2(thanks mark)
%
O00002
N5 T505 (RADIAL LIVE TOOL .1875 ENDMILL)
( G241 - RADIAL DRILLING)
G54
M19 P0
M133 P500
G98
G00 X6. Z-0.75
G241 R4. X2. F20.
Z-1.2
G00 G80 Z1.
G00 G53 X0.
M135
G00 X8. Z8.
M135
M30
%
worked. woop woop

test #3 (thanks again mark, lol)
%
O00002
N5 T505 (RADIAL LIVE TOOL .1875 ENDMILL)
(G243 - RADIAL PECK DRILLING )
G54
M154
M133 P500
G98
G00 G53 X-2.
G00 C0.
G01 X6. Z0. Y0. C0. F30.
G00
G243 R5. X3. F30. I0.5 J0.2 K0.2
Y-2.
Y0. Z-1. C180.
G00 G80
G00 C0.
G00 X8. Z8.
M135
M30
%

so im going to try and see if i can put correct locations and actually drill a part

[The Wolf!]

in the second test what is the p0 after the m19 for? i have to figure out what code the machine wants for rotating the spindel 180 degrees???????

and correct me if im wrong
G241 R4. X2. F20.

g241 drill cycle(spot, drill ??????????)
r 4. is safe start distance on 4" round?
x2. would be drill depth to 2" diameter?

thanks for the help everyone. i think we are close

[The Wolf!]

Attachment 211688

this is the practice part. would like to figure out how to mill the flat radial also(remember i do not have y axis) but could the x go in and out as the spindel turns to get me close? i realize the flat will not be perfectly flat.

running the .830 dia as z0, and the flat is closest to the chuck

[The Wolf!]

ok so i can get the drill and peck cycle to work, but not the rotation of the spindle. c command alarms out. h command does NOT move spindle, but in the position page, i see the number going to 180 in the c axis???????

[The Wolf!]

[QUOTE=The Wolf!;1392234]
used m154 to lock the spindel and it worked.
thanks for the help boyz. would still like to see about milling a flat on the od using radial tool.
feel free to chime in.