[jrick]

I have more than 100 programs created with alphaCam,
Each of them perform a routine twice, once on each side of table.
This allows operator to remove and replace stock on one side while otherside is being cut.
I now need to edit each by adding code after the first operation that;
1) raises the head? (may not be correct term)
2)moves the head to a specified location like X10,y20,z0
3) turns off spindle and wait for input to repeat first operation.

Due to changes in our process we are now using just one side of table and operator stops the machine by breaking light curtain, turns machine to manual, raises spindle, turns it off and moves head out of the way to remove and replace stock. hits reset on the consol for the program then starts the routine over.

I would like to have this done automatically and just have the machine wait for operator to change stock and press the cycle start button.

I did not see a way to post attachment and was not sure if I should post code in this block

advice please.

[fordav11]

Can't you just add something like this to the end of the program?

G0 Z20.0 (RAISE HEAD)
G0 X0 Y20.0 (MOVE TO A SPECIFIC LOCATION)
M5 (SPINDLE OFF)
M0 (WAIT)
M99 (REPEATS THIS PROGRAM FROM THE BEGINNING)
M30 (WILL NEVER REACH THIS)

[jrick]

yes yes yes, I am sure this is what I am looking for. just one issue I can not find. There is another vertical movement other than the z axis that must be made before I cross the center of the table where there is fixturing that will be hit by tool. On the operator control panel (Andi Machine) there are two buttons one turns spindle off, the other raises the whole head where motor and spindle are mounted. I found from your code and looking at mine and the book that My spindle off is M15 because I have two spindles and spindle one is the only one we use, just like tools are refferenced T15 spindle one tool 5.
But that looks like 99.9 percent of what I need.

[TheHitman04]

with turning, you can use

G30 U0.0 W0.0

this is a pre defined safe position for the axes like the reference postion (dont actually know if it goes to the reference) , if you write all the axes in the one G30 line it will move them all together which may collide with a job etc so you'd write it as

G30 U0.0
G30 W0.0

That way it would return the X axis first, then the Z axis, depending on which axis you want to move first just enter that one before the other. Once returned you can use what fordav11 said,

M5; ( Depending on which spindle)
M0;
M99;

Hope this helps

[Superman]

You can modify fordav's code


G0 G28 G91 Z0. (RAISE HEAD to Z HOME REFERENCE POSITION)
G0 G28 G91 Y0. ( Move table to Y HOME REFERENCE POSITION )
G90 ( switch back to absolute mode )
G0 Xxx.xx M9 (Move to a specific X location in the active co-ordinate system, turn coolant OFF )
M5 (SPINDLE OFF)
M00 ( program stop, PRESS cycle start to continue )
M99 (REPEATS THIS PROGRAM FROM THE BEGINNING)
M30 (WILL NEVER REACH THIS)

[jrick]

Thanks everyone, with your help I learned enough to find the rest in manual. FYI the movement I was looking for was listed as M-Code, spindle function; 1--spindle down, 2-spindle up 3-spindle on and as listed already 5-spindle off. So I just need to insert M12 to rease spindle one up, I suppose I will put it at the beginning. thanks everyone again.

[mactec54]

jrick

G0 Z20.0 (RAISE HEAD)
G0 X0 Y20.0 (MOVE TO A SPECIFIC LOCATION)
M5 (SPINDLE OFF)
M9 (if you are using coolant)
M30 (Program rewind) waits for you to press start)

This is all you need nothing else is needed

[jrick]

SORRY MACTEC54 GO Z20.0 YIELDS AN OVERTRAVEL ALARM ON Z AXIS.
TRIED YOUR CODE. i ADDED M12 THIS RAISED THE HEAD AS I NEED
BUT THEN IT DID NOT MOVE TO X OR Y LOCATIONS.

[mactec54]

jrick

If it gives you an over travel you just ajust the numbers to suit your machine
Like G0 Z3. or Z0.0

If your machine does not have 20.00in of travel in the Z axes it sure is going to alarm out

What control do you have, & are you using metric or Inch

[fordav11]

hmmm yes. the X Y Z numbers we are giving you are just examples.
you are supposed to change them to suit your situation....