584,865 active members*
5,034 visitors online*
Register for free
Login
Results 1 to 5 of 5
  1. #1
    Join Date
    Sep 2010
    Posts
    0

    programming question

    how could one get tool diameter offsets to load into offset page thru the program, sometimes operators forget to do this, want to control this if possible, thanks.

  2. #2
    Join Date
    Nov 2007
    Posts
    188

    Programmed Tool Offest

    G10 L10--Programmed Tool Offest Input
    G10 L10 P_X_(U_)Z_(W_)Y_(V_)R_(C_)Q_;

    P offest #
    X x axis offset , absolute
    U x axis offset, incremental
    Z z axis offest, absolute
    W z axis offset, incr.
    Y y axis offset, abs
    V y axis offset, incr.
    R tool nose rad comp amount , abs.
    C tool nose rad comp amount, incr.
    Q Hypothetical tool nose point

    L value is optional
    G11 cancels

    L2 is for work offsets,
    L20 is for additional work offsets (on milling machines only),
    L10 is for H-geometry,
    L11 is for H-wear,
    L12 is for D-geometry,
    L13 is for D-wear,
    No L is used for lathe compensation values,
    L50 is for parameter entry, and
    L3 is for tool life data entry.
    L1 can be used in place of L11.

  3. #3
    Join Date
    Dec 2008
    Posts
    717
    Check your manual. This is right out of it...



    G10 Set Offsets (Group 00)
    G10 allows the programmer to set offsets within the program. Using G10
    replaces the manual entry of offsets (i.e. Tool length and diameter, and work
    coordinate offsets).
    L – Selects offset category.
    L2 Work coordinate origin for G52 and G54-G59
    L10 Length offset amount (for H code)
    L1 or L11 Tool wear offset amount (for H code)
    L12 Diameter offset amount (for D code)
    164 96-8000 Rev AK
    May 2011
    L13 Diameter wear offset amount (for D code)
    L20 Auxiliary work coordinate origin for G110-G129
    P – Selects a specific offset.
    P1-P100 Used to reference D or H code offsets (L10-L13)
    P0 G52 references work coordinate (L2)
    P1-P6 G54-G59 references work coordinates (L2)
    P1-P20 G110-G129 references auxiliary coordinates (L20)
    P1-P99 G154 P1-P99 reference auxiliary coordinate (L20)
    R Offset value or increment for length and diameter.
    X Optional X-axis zero location.
    Y Optional Y-axis zero location.
    Z Optional Z-axis zero location.
    A Optional A-axis zero location.
    Programming Examples
    G10 L2 P1 G91 X6.0 {Move coordinate G54 6.0 to the right};
    G10 L20 P2 G90 X10. Y8. {Set work coordinate G111 to X10.0 ,Y8.0};
    G10 L10 G90 P5 R2.5 {Set offset for Tool #5 to 2.5};
    G10 L12 G90 P5 R.375 {Set diameter for Tool #5 to .375”};
    G10 L20 P50 G90 X10. Y20. {Set work coordinate G154 P50 to X10. Y20.}



    Looks like Chucker said the same thing while I was sidetracked with something else...
    Tim

  4. #4
    Join Date
    Apr 2005
    Posts
    713
    Or a much less confusing way:

    #2001-#2200 are tool lengths
    #3301-#2400 are tool length wear
    #2401-#2600 are tool diameter
    #2601-#2800 are tool diameter wear

    So to set T10 to 3.500" length and .501" diameter either:

    #2010=3.5
    #2410=.5
    #2610=.001

    or

    #2010=3.5
    #2410=.501

    That's less confusing to me, anyway.

    You can also set your Pcool position the same way if you like: #3401-#3600.
    You can also set your work offsets the same way if you're using a permanent sub plate that locates fixtures / vises the same place every time that job is run.

  5. #5
    Join Date
    Sep 2010
    Posts
    0
    thanks for the help

Similar Threads

  1. Programming Question
    By pgf545 in forum HURCO
    Replies: 15
    Last Post: 03-16-2009, 09:10 PM
  2. T-Plus programming question??
    By Bobesmo in forum Mazak, Mitsubishi, Mazatrol
    Replies: 3
    Last Post: 09-27-2007, 10:03 PM
  3. Programming question
    By g-codeguy in forum Fanuc
    Replies: 4
    Last Post: 06-06-2007, 12:16 AM
  4. Programming Question
    By toolmach in forum Mazak, Mitsubishi, Mazatrol
    Replies: 4
    Last Post: 04-08-2007, 01:37 AM
  5. Programming question
    By AMCjeepCJ in forum Milltronics
    Replies: 6
    Last Post: 01-10-2006, 04:58 PM

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •