Adding Custom Drill Cycle to MCX6

I am wanting to add a custom drill cycle to MCX6 to use a deburr tool (this one - Power Deburring Tools | MSCDirect.com) at the top and bottom of the hole. The pilot length is 0.680". The length from the tip to the back of the blade is 1.000". The code to run the tool looks basically like:

G01 Z-0.68 F10.
G04 P0500
G01 Z-1.125
G01 Z-1.
G04 P0500

I have edited the post processor at the Post Text for:
[CTRL_MILL|GENERIC HAAS 3X MILL TEST]

[drill cycle 9]
1. "Deburr - Special Cycle"
7. ""
8. ""
9. ""
10. ""
11. ""
[drill cycle descriptions]
9. "Deburr - Special Cycle"

So, now it shows up in my cut parameters as a cycle (see attachment). What I can't figure out is how to define the custom drill parameters in the post processor. Then I know I need to figure out how to apply those parameters in the post processor to output the code desired.

Kind of busy with other things at the moment. No idea when I might can get back to this.

I found in the NCI file where it outputs the data for the custom drill parameters:

20700
0 0 0 0 0 0 0 0 0 0
1001
0 100 10 90 90 90 0 7601 72.979104 0 0. 0. 0.1 10. 10. 10. 0 0.
0
0 0. 0. 0.1 -2. 0
82
1. 2. 3. 4. 5. 0. 0. 0. 0. 0. <<<<<custom drill parameters #1 - #10
81
8 0. 0. -0.41 0.5 72.979104 0.1 0.1 0.1 0.1 0.1 0.1 0. 0.1 0. 0. 0.1 3000 0 0.
80

Do you have the MP Post Reference guide? If you do not, I would suggest getting it.

The information in the guide will help you to get what you are looking for.

Thanks. I am sure that information will lead to more questions. But it is a good start. Maybe I can work on it some more in the next couple of days.

If you look through the existing drill cycles you can match them up with the pages from the document. That will help you understand what is going on and what is needed.

I think that you can get the post reference guide from your reseller. They give them away for free. It is from V9 but any changes that have been made or added are in the documentation with the current version of Mastercam.

Got the custom cycle added into the post text section and it shows up in the drilling operations now under [drill cycle 9].

# --------------------------------------------------------------------------
# POST TEXT
# --------------------------------------------------------------------------
[CTRL_MILL|GENERIC HAAS 3X MILL TEST]
[misc integers]
1. "Work Coordinates [0-1=G92, 2=G54's]"//2
2. "Absolute/Incremental, top level [0=ABS, 1=INC]"
3. "Reference Return [0=G28, 1=G30]"
[simple drill]
1. "Drill/Counterbore"
7. ""
8. ""
9. ""
10. ""
11. ""
[peck drill]
3. ""
7. "Peck"
8. ""
9. ""
10. ""
11. ""
[chip break]
3. ""
7. "Peck"
8. ""
9. ""
10. ""
11. ""
[tap]
3. ""
7. ""
8. ""
9. ""
10. ""
11. ""
[bore1]
1. "Bore #1 (feed-out)"
7. ""
8. ""
9. ""
10. ""
11. ""
[bore2]
1. "Bore #2 (stop spindle, rapid out)"
3. ""
7. ""
8. ""
9. ""
10. ""
11. ""
[misc1]
1. "Fine Bore (shift)"
7. ""
8. ""
9. ""
10. ""
[misc2]
1. "Rigid Tapping Cycle"
3. ""
7. ""
8. ""
9. ""
10. ""
11. ""
[drill cycle 9]
1. "Deburr - Special Cycle"
2. ""
3. "Dwell"
4. ""
5. ""
6. "Chamfer depth"
7. "Pilot length"
8. "Back blade length"
9. "Part thickness"
10. "Clearance"
11. ""
[drill cycle descriptions]
1. ""
2. ""
3. ""
4. ""
5. ""
6. ""
7. "Fine bore (shift)"
8. "Rigid Tapping Cycle"
9. "Deburr - Special Cycle"
[canned text]
1. "Stop"
2. "Ostop"
3. "Bld on"
4. "bLd off"
5. "M5"
6. "M6"
7. "M7"
8. "M8"
9. "M9"
10. "M10"
[CTRL_TEXT_END]

Now working on how to impliment it to output the code. Any idea what the variable is for "Top of Stock"? I need to use that for a calculation in the post. I know the other variables are:

initht$ - Clearance
refht$ - Retract
pfzout - Depth
peck1$ - 1st peck
peck2$ - Subsequent peck
peckclr$ - Peck clearance
retr$ - Retract amount
dwell$ - Dwell
*feed - Feed

Besides Top of Stock, what else might I be missing?

tosz (tosz$) is the "absolute" position of the Z location of the top of stock

Thanks. That helps.